Rebuild failure and drawing association in a sensor enclosure model
A transition-year team is preparing a wall-mounted sensor enclosure for small-batch production. The enclosure is 180 mm × 120 mm × 45 mm externally, with 2.4 mm ABS walls, four M3 brass inserts in 8 mm-diameter bosses, a 0.8 mm-deep recessed logo on the front face, and a 1.6 mm snap-fit cantilever on one side. The CAD model was built by creating the outer solid, adding the logo recess, shelling the solid to 2.4 mm, then adding the bosses and snap fit. The team now wants a 2.0 mm wall to save material. When the wall thickness is changed, the shell feature fails and one corner of the logo recess reports a zero-thickness error. The associated drawing’s section B–B does not update, and the hole table lists two identical M3 callouts for the same boss. The model must be sent to an FDM printer and to a machinist who will cut the front panel from 3 mm polycarbonate. The team has one week before the design review.
1. Diagnose the shell failure and zero-thickness error, and propose a robust feature order.
Read the worked answer
The shell fails because the logo recess is a face cut that leaves a local step in the solid before shelling. When the wall is reduced from 2.4 to 2.0 mm, the offset surface on the recessed face intersects the opposite face at one corner, giving a zero-thickness error. The robust order is: create the outer solid with simple, clean faces; shell it to 2.0 mm, removing the back face; add the bosses as separate bodies or as join features, with an outer diameter of at least twice the wall plus the hole diameter; add fillets after the shell; cut the logo as a 0.8 mm engraving into the 2.0 mm wall, leaving 1.2 mm of material; add the snap-fit last, because it is the most dimension-sensitive feature. If the logo must be a recess, model it after shell and check minimum remaining wall. Avoid building thin cosmetic features before shell, because shell offsets every face and amplifies small steps.
2. Explain why section B–B and the hole table fail to update, and state what should change in the CAD drawing.
Read the worked answer
Section B–B is not updating because it was drawn as manual lines on the drawing sheet rather than as an associated section view. The hole table is also manual or has been generated from two separate hole features that occupy the same boss. In a parametric CAD drawing, the section line must be created with the section-view tool and attached to the parent view; then it will follow changes to the model. The hole table should be driven by a hole feature or pattern, not by manually added callouts. Remove duplicate callouts by making the four insert holes one pattern and using a single table entry “4 × M3”. After changing the wall, rebuild the model, update the drawing views, and check that the section arrows still point in the correct direction. Manual annotation is acceptable only for notes that are not geometry-driven.
3. Recommend export formats and settings for the FDM printer and the machinist.
Read the worked answer
For the machinist, export a solid format such as STEP AP214 or AP242, together with a PDF drawing that has the 3 mm polycarbonate front-panel dimensions, hole positions and tolerances. Do not send an STL for machining; it is a mesh and loses exact feature information. For the FDM printer, export STL (binary) or 3MF with a chord tolerance of about 0.02 mm and an angle tolerance of 5°, and check that the mesh is manifold. The 2.0 mm wall is five times a 0.4 mm nozzle, which is printable, but the 8 mm bosses need a hole size matched to the brass insert - for example 4.0 mm for an M3 heat-set insert, not 3.0 mm. Orient the enclosure so the snap-fit cantilever lies in the XY plane to avoid delamination. State the material, layer height and insert fit on the drawing so the printer and machinist are working from the same revision.